Embossed features
Local sheet-metal forms: geometry, process distinctions, tooling limits and functional acceptance.
Tags: parts-and-design, sheet-metal, forming, embossing
On this page
Define the feature and intended function
Specify raised or recessed geometry from the identified face, with height, footprint and transitions.
Illustrative screening calculation: using CONIC’s dimple guide, assume diameter A = 12 mm and sheet thickness t = 1.5 mm. The two height bounds become H < 4.8 mm and H < 4.5 mm. A proposed 4.0 mm height is below both; 4.5 mm does not meet the strict second inequality. Passing this arithmetic does not establish tool access, ductility, radii, dimensional capability or successful forming.
Mate distinguishes formed embossing from cold-forge embossing. Its description says formed embossing bends material around the tool, stretching and compressing surfaces as direction changes, while also drawing material into the form. It lists raised hardware-clearance areas, dimples and logos as examples. These are process descriptions and application examples, not universal performance claims. No technical revision date was verified on the webpage. Mate, forming tools and applications
Record whether the feature is raised or recessed from the identified face. A protrusion viewed from one side can be a recess from the other; “up” without an orientation reference is ambiguous.
Processes and feature families
| Feature/process | Distinction to preserve |
|---|---|
| Formed emboss or dimple | Local displaced sheet geometry, with defined height, footprint and transitions. |
| Bead | An elongated formed feature, potentially made with repeated or rolling tool motion. |
| Cold-forged text/design | Local displacement using a different tool action from a drawn hollow form. |
| Cut-and-formed feature | Openings and free edges must be specified separately from the formed surface. |
Mate's Technical Solutions Guide, LIT00682 revision E, printed 2021, explains cold-forged lettering as a punch stroke stopped before fracture and slug separation. Its stated maximum raise of up to 50% of sheet thickness depends on ductility. That is not the same process or limit as a formed emboss whose height spans several sheet thicknesses. Mate technical guide, cold-forged emboss section
Choose the actual process with the fabricator. Tool station size, machine capability, material condition and access can determine whether a seemingly simple model is practical. A design that can be represented as a solid does not establish that it can be produced with existing tooling.
Geometry to place on the definition
| Field | What to resolve |
|---|---|
| Material | Alloy/grade, supplied condition, nominal thickness and tolerance. |
| Footprint | Length/width or diameter, location and orientation. |
| Height/depth | Reference surface, sign/direction and acceptance after forming. |
| Transitions | Inside/outside radii, side-wall geometry and permitted thinning where functional. |
| Surroundings | Adjacent holes, bends, edges, contact surfaces and tooling clearance. |
State whether the controlled surface is the crest, the inside cavity, a contact pad or the overall envelope. Tool geometry, internal geometry and external geometry should not be substituted for one another. Define a profile or section where a single height cannot capture the functional shape.
Maintain a clear reference to the undeformed sheet or another stable datum. If neighboring sheet distortion affects assembly, specify the required surrounding shape as well as emboss height. A correct crest height alone does not establish a flat mounting panel.
Bounded tooling guidance
CONIC's Emboss (Dimple) guide describes positioning and decorative forms. Its diagram uses height H and diameter A, with preferences H < 0.40A and H < 3t, where t is material thickness. The actual drawing must preserve those dimension definitions. No issue date was verified on the live guide. These are CONIC tooling preferences, not universal forming limits or a material-independent acceptance rule. CONIC emboss technical guide
Mate's separate special-applications overview recommends keeping form height low to minimize sheet distortion. For its formed emboss category it describes best results at side-wall angles of 45° or less and an optimum height at or below three material thicknesses. Keep the supplier's diagram and terminology with those values; do not blend them into another toolmaker's rule. The webpage has no verified issue date. Mate special-applications overview
Beads and stiffness claims
A bead can change panel geometry and response, but its benefit depends on direction, load, supports and the surrounding design. Do not assign a universal percentage stiffness increase or reduce thickness solely because a catalogue lists stiffening as an application.
TRUMPF's punching-tool catalogue describes a beading tool producing continuous beads in nibbling mode and lists specific machine compatibility and a sheet-thickness range. This shows why a bead is also a process/tooling selection. The cited filename includes 2023; a separate printed revision date was not independently verified, so it is not treated as edition proof. TRUMPF punching-tool catalogue, beading tool
If stiffness, vibration response or contact behavior is important, compare the complete embossed panel with its required loading and restraints. Forming feasibility and structural adequacy are separate decisions.
CAD and flat-pattern boundaries
SOLIDWORKS 2026 Help treats forming tools as sheet-metal features with placement/orientation controls. It warns that a tool can fail when a pushed-in concave radius is smaller than material thickness, or when the form intersects bends or other geometry outside the planar region. These are software geometry constraints, not validated physical formability criteria. SOLIDWORKS 2026, applying forming tools
Model both faces and inspect the transition region. Agree how the feature is represented in the flat-pattern deliverable: a locating outline, forming annotation or another fabricator-approved convention must not be mistaken for an unintended through-cut. Retain the formed model or section when the outline alone is insufficient.
Process review and acceptance
Review material flow, forming sequence, neighboring-feature distortion, tool access and surface protection with the fabricator. A feature near a bend or opening needs evaluation as part of the complete layout. Avoid generic spacing or draw-depth limits without a source tied to the selected process.
- Identify the functional surface and material/condition.
- Define height, footprint, radii, direction and datums.
- Obtain tooling/process review for the actual thickness and layout.
- Evaluate required strength, fit or appearance separately from formability.
- Inspect finished geometry, surrounding distortion, surfaces and agreed defect limits.
For agent-readable records, distinguish a formed emboss, a bead and a cold-forged mark. Store tool/process identity, source revision, dimension references and acceptance stage alongside the CAD geometry. A supplier preference, software constraint and contractual requirement should remain separate fields.